The Designer's Guide Community
Forum
Welcome, Guest. Please Login or Register. Please follow the Forum guidelines.
Oct 21st, 2020, 6:23pm
Pages: 1
Send Topic Print
Unexpected value of noise (Read 2472 times)
Vladislav D
Community Member
***
Offline



Posts: 76
The Netherlands
Unexpected value of noise
Jun 10th, 2010, 1:16pm
 
We all know that the output noise of two resistor is 4*k*T*(R1 || R2). So, if both resistors have value of 50 Ohms, the output noise is 0.644nV/sqrt(Hz) (T=300K). If I simulate the circuit with two resistors and a voltage source I get the same result, however, if I substitute series resistor and voltage source with 50-Ohms port the output noise becomes 638nV/sqrt(Hz). I cannot find the explanation of this effect. Is this bug or I missed something?
Back to top
« Last Edit: Jun 10th, 2010, 2:23pm by Vladislav D »  

noise.PNG
View Profile   IP Logged
rfcooltools.com
Senior Member
****
Offline



Posts: 159

Re: Unexpected value of noise
Reply #1 - Jun 10th, 2010, 9:56pm
 
In Cadence the port has its own temperature.  you may want to check what the default is set to.

http://rfcooltools.com
Back to top
 
 
View Profile   IP Logged
pancho_hideboo
Senior Fellow
******
Offline



Posts: 1424
Real Homeless
Re: Unexpected value of noise
Reply #2 - Jun 12th, 2010, 7:52am
 
I can't find out any design isuue in your question.
Your question is no more than very easy issue of very specific vendor's simulator.

What simulator do you use ?

Vladislav D wrote on Jun 10th, 2010, 1:16pm:
if I substitute series resistor and voltage source with 50-Ohms port
the output noise becomes 638nV/sqrt(Hz).

Vout2=4*k*{R2/(R1+R2)}2*(R1*T1+R2*T2)
Here R1 and T1 mean resistance and temperature of "port" respectively.

If R1=R2=50, Vout2=50*k*(T1+T2)

If T1=T2=300K, Vout=643.6[pVrms/sqrt(Hz)].

If T1=290K, T2=300K, Vout=638.2[pVrms/sqrt(Hz)].

See http://www.designers-guide.org/Forum/YaBB.pl?num=1192525133/10#10



The followings are general notes for you.

- Always describe correct tool's name and vendor's name which you use as tool or simulator.
- Don't do multiple posts which are same content.
- Don't request source code or behavioral model without any efforts.
- There are many simulators which have analyses called as PSS, PAC and Pnoise.
- Describe in detail with using correct terminologies.
- Warnigns are different from Errors.
- ADS is not name of simulator.
- There is no tool which name is Cadence.
- Don't use Direct Plot of Cadence ADE blindly without knowing definition.
- All gains in Direct Plot of Cadence ADE are "right", "true" and "practical" voltage gain.
- Don't mix up Simulation with Post Processing. They are completely different phase.
- MATLAB are different from Simulink.
- Learn measurements using actual instruments. Not "EDA Tool Play
Back to top
 
« Last Edit: Jun 12th, 2010, 8:58am by pancho_hideboo »  
View Profile WWW Top+Secret Top+Secret   IP Logged
pancho_hideboo
Senior Fellow
******
Offline



Posts: 1424
Real Homeless
Re: Unexpected value of noise
Reply #3 - Jun 14th, 2010, 6:07am
 
Agilent ADSsim treat temperature of port as analysis temperature, if it is not specified for all analyses except for SP-Analysis.
In SP-Analysis of Agilent ADSsim, ADSsim treats port temperature as 290[K] even if you set any value as port temperature.

Again see http://www.designers-guide.org/Forum/YaBB.pl?num=1192525133/10#10
Back to top
 

test_port_noise.png
View Profile WWW Top+Secret Top+Secret   IP Logged
Pages: 1
Send Topic Print
Copyright 2002-2020 Designer’s Guide Consulting, Inc. Designer’s Guide® is a registered trademark of Designer’s Guide Consulting, Inc. All rights reserved. Send comments or questions to editor@designers-guide.org. Consider submitting a paper or model.